This fvModel applies an explicit forcing force to components of the vector field in the direction of gravity. Its intended purpose is to damp the vertical motions of an interface in the region approaching an outlet so that no reflections are generated. More...

Inheritance diagram for verticalDamping:

[legend]

Collaboration diagram for verticalDamping:

[legend]

Public Member Functions
	TypeName ("verticalDamping")
	Runtime type information. More...

	verticalDamping (const word &name, const word &modelType, const fvMesh &mesh, const dictionary &dict)
	Construct from components. More...

virtual	~verticalDamping ()
	Destructor. More...

virtual wordList	addSupFields () const
	Return the list of fields for which the fvModel adds source term. More...

virtual void	addSup (fvMatrix< vector > &eqn, const word &fieldName) const
	Source term to momentum equation. More...

virtual void	addSup (const volScalarField &rho, fvMatrix< vector > &eqn, const word &fieldName) const
	Source term to compressible momentum equation. More...

virtual void	addSup (const volScalarField &alpha, const volScalarField &rho, fvMatrix< vector > &eqn, const word &fieldName) const
	Source term to phase momentum equation. More...

virtual bool	movePoints ()
	Update for mesh motion. More...

virtual void	topoChange (const polyTopoChangeMap &)
	Update topology using the given map. More...

virtual void	mapMesh (const polyMeshMap &)
	Update from another mesh using the given map. More...

virtual void	distribute (const polyDistributionMap &)
	Redistribute or update using the given distribution map. More...

Public Member Functions inherited from forcing
	TypeName ("forcing")
	Runtime type information. More...

	forcing (const word &name, const word &modelType, const fvMesh &mesh, const dictionary &dict)
	Construct from components. More...

virtual	~forcing ()
	Destructor. More...

virtual bool	read (const dictionary &dict)
	Read dictionary. More...

Public Member Functions inherited from fvModel
	TypeName ("fvModel")
	Runtime type information. More...

	declareRunTimeSelectionTable (autoPtr, fvModel, dictionary,(const word &name, const word &modelType, const fvMesh &mesh, const dictionary &dict),(name, modelType, mesh, dict))

	fvModel (const word &name, const word &modelType, const fvMesh &mesh, const dictionary &dict)
	Construct from components. More...

autoPtr< fvModel >	clone () const
	Return clone. More...

virtual	~fvModel ()
	Destructor. More...

const word &	name () const
	Return const access to the source name. More...

const fvMesh &	mesh () const
	Return const access to the mesh database. More...

const dictionary &	coeffs () const
	Return dictionary. More...

virtual bool	addsSupToField (const word &fieldName) const
	Return true if the fvModel adds a source term to the given. More...

virtual scalar	maxDeltaT () const
	Return the maximum time-step for stable operation. More...

	FOR_ALL_FIELD_TYPES (DEFINE_FV_MODEL_ADD_SUP)
	Add a source term to an equation. More...

	FOR_ALL_FIELD_TYPES (DEFINE_FV_MODEL_ADD_RHO_SUP)
	Add a source term to a compressible equation. More...

	FOR_ALL_FIELD_TYPES (DEFINE_FV_MODEL_ADD_ALPHA_RHO_SUP)
	Add a source term to a phase equation. More...

template<class Type >
tmp< fvMatrix< Type > >	source (const VolField< Type > &field) const
	Return source for an equation. More...

template<class Type >
tmp< fvMatrix< Type > >	source (const VolField< Type > &field, const word &fieldName) const
	Return source for an equation with a specified name. More...

template<class Type >
tmp< fvMatrix< Type > >	source (const volScalarField &rho, const VolField< Type > &field) const
	Return source for a compressible equation. More...

template<class Type >
tmp< fvMatrix< Type > >	source (const volScalarField &rho, const VolField< Type > &field, const word &fieldName) const
	Return source for a compressible equation with a specified name. More...

template<class Type >
tmp< fvMatrix< Type > >	source (const volScalarField &alpha, const volScalarField &rho, const VolField< Type > &field) const
	Return source for a phase equation. More...

template<class Type >
tmp< fvMatrix< Type > >	source (const volScalarField &alpha, const volScalarField &rho, const VolField< Type > &field, const word &fieldName) const
	Return source for a phase equation with a specified name. More...

template<class Type >
tmp< fvMatrix< Type > >	source (const volScalarField &alpha, const geometricOneField &rho, const VolField< Type > &field) const
	Return source for a phase equation. More...

template<class Type >
tmp< fvMatrix< Type > >	source (const geometricOneField &alpha, const volScalarField &rho, const VolField< Type > &field) const
	Return source for a phase equation. More...

template<class Type >
tmp< fvMatrix< Type > >	source (const geometricOneField &alpha, const geometricOneField &rho, const VolField< Type > &field) const
	Return source for a phase equation. More...

template<class Type >
tmp< fvMatrix< Type > >	d2dt2 (const VolField< Type > &field) const
	Return source for an equation with a second time derivative. More...

template<class Type >
tmp< fvMatrix< Type > >	d2dt2 (const VolField< Type > &field, const word &fieldName) const
	Return source for an equation with a second time derivative. More...

virtual void	preUpdateMesh ()
	Prepare for mesh update. More...

virtual void	correct ()
	Correct the fvModel. More...

template<class Type , class AlphaRhoFieldType , class ... AlphaRhoFieldTypes>
Foam::dimensionSet	sourceDims (const VolField< Type > &field, const dimensionSet &ds, const AlphaRhoFieldType &alphaRho, const AlphaRhoFieldTypes &... alphaRhos)

template<class Type >
Foam::dimensionSet	sourceDims (const VolField< Type > &field, const dimensionSet &ds)

template<class Type , class ... AlphaRhoFieldTypes>
Foam::tmp< Foam::fvMatrix< Type > >	source (const VolField< Type > &field, const word &fieldName, const dimensionSet &ds, const AlphaRhoFieldTypes &... alphaRhos) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	source (const VolField< Type > &field) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	source (const VolField< Type > &field, const word &fieldName) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	source (const volScalarField &rho, const VolField< Type > &field) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	source (const volScalarField &rho, const VolField< Type > &field, const word &fieldName) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	source (const volScalarField &alpha, const volScalarField &rho, const VolField< Type > &field) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	source (const volScalarField &alpha, const volScalarField &rho, const VolField< Type > &field, const word &fieldName) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	source (const geometricOneField &alpha, const geometricOneField &rho, const VolField< Type > &field) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	source (const volScalarField &alpha, const geometricOneField &rho, const VolField< Type > &field) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	source (const geometricOneField &alpha, const volScalarField &rho, const VolField< Type > &field) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	d2dt2 (const VolField< Type > &field) const

template<class Type >
Foam::tmp< Foam::fvMatrix< Type > >	d2dt2 (const VolField< Type > &field, const word &fieldName) const

Additional Inherited Members
Static Public Member Functions inherited from fvModel
template<class Type , class AlphaRhoFieldType , class ... AlphaRhoFieldTypes>
static dimensionSet	sourceDims (const VolField< Type > &field, const dimensionSet &ds, const AlphaRhoFieldType &alphaRho, const AlphaRhoFieldTypes &... alphaRhos)
	Return the dimensions of the matrix of a source term. More...

template<class Type >
static dimensionSet	sourceDims (const VolField< Type > &field, const dimensionSet &ds)
	Return the dimensions of the matrix of a source term (base. More...

static autoPtr< fvModel >	New (const word &name, const fvMesh &mesh, const dictionary &dict)
	Return a reference to the selected fvModel. More...

Protected Member Functions inherited from forcing
void	readCoeffs ()
	Non-virtual read. More...

tmp< volScalarField::Internal >	scale () const
	Return the scale distribution. More...

tmp< volScalarField::Internal >	forceCoeff (const volScalarField::Internal &scale) const
	Return the force coefficient given the scale distribution. More...

tmp< volScalarField::Internal >	forceCoeff () const
	Return the force coefficient. More...

Protected Member Functions inherited from fvModel
template<class Type >
void	addSupType (fvMatrix< Type > &eqn, const word &fieldName) const
	Add a source term to an equation. More...

template<class Type >
void	addSupType (const volScalarField &rho, fvMatrix< Type > &eqn, const word &fieldName) const
	Add a source term to a compressible equation. More...

template<class Type >
void	addSupType (const volScalarField &alpha, const volScalarField &rho, fvMatrix< Type > &eqn, const word &fieldName) const
	Add a source term to a phase equation. More...

template<class Type , class ... AlphaRhoFieldTypes>
tmp< fvMatrix< Type > >	source (const VolField< Type > &field, const word &fieldName, const dimensionSet &ds, const AlphaRhoFieldTypes &... alphaRhos) const
	Return source for equation with specified name and dimensions. More...

Protected Attributes inherited from forcing
dimensionedScalar	lambda_
	Damping coefficient [1/s]. More...

dimensionedScalar	lambdaBoundary_
	Optional boundary damping coefficient [1/s]. More...

autoPtr< Function1< scalar > >	scale_
	The scaling function. More...

vectorField	origins_
	Origins of the scaling coordinate. More...

vectorField	directions_
	Directions of increasing scaling coordinate. More...

Detailed Description

This fvModel applies an explicit forcing force to components of the vector field in the direction of gravity. Its intended purpose is to damp the vertical motions of an interface in the region approaching an outlet so that no reflections are generated.

Damping is achieved by applying a force to the momentum equation proportional to the momentum of the flow in the direction of gravity. The constant of proportionality is given by a coefficient $\lambda$ which has units of inverse-time. In the absence of any other forces this would generate an exponential decay of the vertical velocity.

$\frac{d (m u_z)}{d t} = - \lambda m u_z$

$u_z = u_{z0} e^{- \lambda t}$

The coefficient $\lambda$ should be set based on the desired level of forcing and the residence time of a perturbation through the forcing zone. For example, if waves moving at 2 [m/s] are travelling through a forcing zone 8 [m] in length, then the residence time is 4 [s]. If it is deemed necessary to damp for 5 time-scales, then $\lambda$ should be set to equal 5/(4 [s]) = 1.2 [1/s].

Usage

Example usage:

verticalDamping1
{
    type            verticalDamping;

    libs            ("libwaves.so");

    // Define the line along which to apply the graduation
    origin          (1200 0 0);
    direction       (1 0 0);

    // Or, define multiple lines
    // origins         ((1200 0 0) (1200 -300 0) (1200 300 0));
    // directions      ((1 0 0) (0 -1 0) (0 1 0));

    scale
    {
        type        halfCosineRamp;
        start       0;
        duration    600;
    }

    lambda          [0 0 -1 0 0 0 0] 1; // Damping coefficient

    timeStart       0;
    duration        1e6;
}

See also: Foam::fv::forcing Foam::fv::isotropicDamping

Source files

Definition at line 108 of file verticalDamping.H.

Constructor & Destructor Documentation

◆ verticalDamping()

verticalDamping	(	const word &	name,
		const word &	modelType,
		const fvMesh &	mesh,
		const dictionary &	dict
	)

Construct from components.

Definition at line 62 of file verticalDamping.C.

◆ ~verticalDamping()

virtual ~verticalDamping ( )

inlinevirtual

Destructor.

Definition at line 147 of file verticalDamping.H.

Member Function Documentation

◆ TypeName()

TypeName ( "verticalDamping" )

Runtime type information.

◆ addSupFields()

Foam::wordList addSupFields ( ) const

virtual

Return the list of fields for which the fvModel adds source term.

to the transport equation

Reimplemented from fvModel.

Definition at line 77 of file verticalDamping.C.

◆ addSup() [1/3]

void addSup	(	fvMatrix< vector > &	eqn,
		const word &	fieldName
	)		const

virtual

Source term to momentum equation.

Definition at line 83 of file verticalDamping.C.

References Foam::add(), and fvMatrix< Type >::psi().

Here is the call graph for this function:

◆ addSup() [2/3]

void addSup	(	const volScalarField &	rho,
		fvMatrix< vector > &	eqn,
		const word &	fieldName
	)		const

virtual

Source term to compressible momentum equation.

Definition at line 93 of file verticalDamping.C.

References Foam::add(), fvMatrix< Type >::psi(), and rho.

Here is the call graph for this function:

◆ addSup() [3/3]

void addSup	(	const volScalarField &	alpha,
		const volScalarField &	rho,
		fvMatrix< vector > &	eqn,
		const word &	fieldName
	)		const

virtual

Source term to phase momentum equation.

Definition at line 104 of file verticalDamping.C.

References Foam::add(), alpha(), fvMatrix< Type >::psi(), and rho.

Here is the call graph for this function:

◆ movePoints()

bool movePoints ( )

virtual

Update for mesh motion.

Implements fvModel.

Definition at line 116 of file verticalDamping.C.

◆ topoChange()

void topoChange ( const polyTopoChangeMap & )

virtual

Update topology using the given map.

Implements fvModel.

Definition at line 122 of file verticalDamping.C.

◆ mapMesh()

void mapMesh ( const polyMeshMap & map )

virtual

Update from another mesh using the given map.

Implements fvModel.

Definition at line 126 of file verticalDamping.C.

◆ distribute()

void distribute ( const polyDistributionMap & )

virtual

Redistribute or update using the given distribution map.

Implements fvModel.

Definition at line 130 of file verticalDamping.C.

The documentation for this class was generated from the following files:

src/waves/fvModels/verticalDamping/verticalDamping.H
src/waves/fvModels/verticalDamping/verticalDamping.C

Public Member Functions

Additional Inherited Members

Detailed Description

Constructor & Destructor Documentation

◆ verticalDamping()

◆ ~verticalDamping()

Member Function Documentation

◆ TypeName()

◆ addSupFields()

◆ addSup() [1/3]

◆ addSup() [2/3]

◆ addSup() [3/3]

◆ movePoints()

◆ topoChange()

◆ mapMesh()

◆ distribute()