codedMixedFvPatchField.H

Go to the documentation of this file.

/*---------------------------------------------------------------------------*\
  =========                 |
  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
   \\    /   O peration     | Website:  https://openfoam.org
    \\  /    A nd           | Copyright (C) 2011-2023 OpenFOAM Foundation
     \\/     M anipulation  |
-------------------------------------------------------------------------------
License
    This file is part of OpenFOAM.
 
    OpenFOAM is free software: you can redistribute it and/or modify it
    under the terms of the GNU General Public License as published by
    the Free Software Foundation, either version 3 of the License, or
    (at your option) any later version.
 
    OpenFOAM is distributed in the hope that it will be useful, but WITHOUT
    ANY WARRANTY; without even the implied warranty of MERCHANTABILITY or
    FITNESS FOR A PARTICULAR PURPOSE.  See the GNU General Public License
    for more details.
 
    You should have received a copy of the GNU General Public License
    along with OpenFOAM.  If not, see <http://www.gnu.org/licenses/>.
 
Class
    Foam::codedMixedFvPatchField
 
Description
    Constructs on-the-fly a new boundary condition (derived from
    mixedFvPatchField) which is then used to evaluate.
 
Usage
    Example:
    \verbatim
    <patchName>
    {
        type            codedMixed;
 
        refValue        uniform (0 0 0);
        refGradient     uniform (0 0 0);
        valueFraction   uniform 1;
 
        name    rampedMixed;   // name of generated BC
 
        code
        #{
            this->refValue() =
                vector(1, 0, 0)
               *min(10, 0.1*this->db().time().value());
            this->refGrad() = Zero;
            this->valueFraction() = 1.0;
        #};
 
        // codeInclude
        //#{
        //    #include ".H"
        //#};
 
        // codeOptions
        //#{
        //    -I$(LIB_SRC)/finiteVolume/lnInclude
        //#};
    }
    \endverbatim
 
    A special form is if the 'code' section is not supplied. In this case
    the code gets read from a (runTimeModifiable!) dictionary system/codeDict
    which would have a corresponding entry
 
    \verbatim
    <patchName>
    {
        code
        #{
            this->refValue() = min(10, 0.1*this->db().time().value());
            this->refGrad() = Zero;
            this->valueFraction() = 1.0;
        #};
    }
    \endverbatim
 
See also
    Foam::dynamicCode
    Foam::functionEntries::codeStream
 
SourceFiles
    codedMixedFvPatchField.C
 
\*---------------------------------------------------------------------------*/
 
#ifndef codedMixedFvPatchField_H
#define codedMixedFvPatchField_H
 
#include "mixedFvPatchFields.H"
#include "codedBase.H"
 
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
 
namespace Foam
{
 
/*---------------------------------------------------------------------------*\
                   Class codedMixedFvPatchField Declaration
\*---------------------------------------------------------------------------*/
 
template<class Type>
class codedMixedFvPatchField
:
    public mixedFvPatchField<Type>,
    public codedBase
{
    // Private Data
 
        mutable autoPtr<mixedFvPatchField<Type>> redirectPatchFieldPtr_;
 
 
    // Private Member Functions
 
        //- Get the keywords associated with source code
        virtual wordList codeKeys() const;
 
        //- Adapt the context for the current object
        virtual void prepare(dynamicCode&, const dynamicCodeContext&) const;
 
        //- Clear the ptr to the redirected object
        virtual void clearRedirect() const;
 
 
public:
 
    //- Runtime type information
    TypeName("codedMixed");
 
 
    // Constructors
 
        //- Construct from patch, internal field and dictionary
        codedMixedFvPatchField
        (
            const fvPatch&,
            const DimensionedField<Type, volMesh>&,
            const dictionary&
        );
 
        //- Construct by mapping given codedMixedFvPatchField
        //  onto a new patch
        codedMixedFvPatchField
        (
            const codedMixedFvPatchField<Type>&,
            const fvPatch&,
            const DimensionedField<Type, volMesh>&,
            const fvPatchFieldMapper&
        );
 
 
        //- Disallow copy without setting internal field reference
        codedMixedFvPatchField(const codedMixedFvPatchField<Type>&) = delete;
 
        //- Copy constructor setting internal field reference
        codedMixedFvPatchField
        (
            const codedMixedFvPatchField<Type>&,
            const DimensionedField<Type, volMesh>&
        );
 
        //- Construct and return a clone setting internal field reference
        virtual tmp<fvPatchField<Type>> clone
        (
            const DimensionedField<Type, volMesh>& iF
        ) const
        {
            return tmp<fvPatchField<Type>>
            (
                new codedMixedFvPatchField<Type>(*this, iF)
            );
        }
 
 
    // Member Functions
 
        //- Get reference to the underlying patchField
        const mixedFvPatchField<Type>& redirectPatchField() const;
 
        //- Update the coefficients associated with the patch field
        virtual void updateCoeffs();
 
        //- Evaluate the patch field
        //  This is only needed to set the updated() flag of the name
        //  to false.
        virtual void evaluate
        (
            const Pstream::commsTypes commsType=Pstream::commsTypes::blocking
        );
 
        //- Write
        virtual void write(Ostream&) const;
};
 
 
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
 
} // End namespace Foam
 
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
 
#ifdef NoRepository
    #include "codedMixedFvPatchField.C"
#endif
 
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
 
#endif
 
// ************************************************************************* //