This boundary condition provides a total pressure condition. Four variants are possible: More...

Inheritance diagram for totalPressureFvPatchScalarField:

Collaboration diagram for totalPressureFvPatchScalarField:

Public Member Functions
	TypeName ("totalPressure")
	Runtime type information. More...

	totalPressureFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &)
	Construct from patch and internal field. More...

	totalPressureFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)
	Construct from patch, internal field and dictionary. More...

	totalPressureFvPatchScalarField (const totalPressureFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)
	Construct by mapping given totalPressureFvPatchScalarField. More...

	totalPressureFvPatchScalarField (const totalPressureFvPatchScalarField &)
	Copy constructor. More...

virtual tmp< fvPatchScalarField >	clone () const
	Construct and return a clone. More...

	totalPressureFvPatchScalarField (const totalPressureFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)
	Copy constructor setting internal field reference. More...

virtual tmp< fvPatchScalarField >	clone (const DimensionedField< scalar, volMesh > &iF) const
	Construct and return a clone setting internal field reference. More...

void	updateCoeffs (const scalarField &p0p, const vectorField &Up)
	Update the coefficients associated with the patch field. More...

virtual void	updateCoeffs ()
	Update the coefficients associated with the patch field. More...

virtual void	write (Ostream &) const
	Write. More...

Public Member Functions inherited from dynamicPressureFvPatchScalarField
	TypeName ("dynamicPressure")
	Runtime type information. More...

	dynamicPressureFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &)
	Construct from patch and internal field. More...

	dynamicPressureFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)
	Construct from patch, internal field and dictionary. More...

	dynamicPressureFvPatchScalarField (const dynamicPressureFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)
	Construct by mapping given dynamicPressureFvPatchScalarField. More...

	dynamicPressureFvPatchScalarField (const dynamicPressureFvPatchScalarField &)
	Copy constructor. More...

	dynamicPressureFvPatchScalarField (const dynamicPressureFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)
	Copy constructor setting internal field reference. More...

virtual void	autoMap (const fvPatchFieldMapper &)
	Map (and resize as needed) from self given a mapping object. More...

virtual void	rmap (const fvPatchScalarField &, const labelList &)
	Reverse map the given fvPatchField onto this fvPatchField. More...

void	updateCoeffs (const scalarField &p0p, const scalarField &Kp)
	Update the coefficients associated with the patch field. More...

Protected Attributes
const word	UName_
	Name of the velocity field. More...

const word	phiName_
	Name of the flux field. More...

Protected Attributes inherited from dynamicPressureFvPatchScalarField
const word	rhoName_
	Name of the density field used to normalise the mass flux. More...

const word	psiName_
	Name of the compressibility field used to calculate the wave speed. More...

const scalar	gamma_
	Heat capacity ratio. More...

scalarField	p0_
	Reference pressure. More...

Detailed Description

This boundary condition provides a total pressure condition. Four variants are possible:

1. incompressible subsonic:

$p_p = p_0 - 0.5 |U|^2$

where

	=	incompressible pressure at patch [m^2/s^2]
	=	incompressible total pressure [m^2/s^2]
	=	velocity [m/s]

2. compressible subsonic:

$p_p = p_0 - 0.5 \rho |U|^2$

where

	=	pressure at patch [Pa]
	=	total pressure [Pa]
$\rho$	=	density [kg/m^3]
	=	velocity [m/s]

3. compressible transonic ( $\gamma = 1$ ):

$p_p = \frac{p_0}{1 + 0.5 \psi |U|^2}$

where

	=	pressure at patch [Pa]
	=	total pressure [Pa]
$\psi$	=	compressibility [m^2/s^2]
	=	velocity [m/s]

4. compressible supersonic ( $\gamma > 1$ ):

$p_p = \frac{p_0}{(1 + 0.5 \psi G |U|^2)^{\frac{1}{G}}}$

where

	=	pressure at patch [Pa]
	=	total pressure [Pa]
$\psi$	=	compressibility [m^2/s^2]
	=	coefficient given by $\frac{\gamma}{1-\gamma}$ []
$\gamma$	=	ratio of specific heats (Cp/Cv) []
	=	velocity [m/s]

The modes of operation are set by the dimensions of the pressure field to which this boundary condition is applied, the psi entry and the value of gamma:

Mode	dimensions	psi	gamma
`incompressible` subsonic	p/rho
`compressible` subsonic	p	none
`compressible` transonic	p	psi	1
`compressible` supersonic	p	psi	> 1

Usage

Property	Description	Required	Default value
`U`	Velocity field name	no	U
`phi`	Flux field name	no	phi
`rho`	Density field name	no	rho
`psi`	Compressibility field name	no	none
`gamma`	(Cp/Cv)	no	1
`p0`	Total pressure	yes

Example of the boundary condition specification:

    <patchName>
    {
        type            totalPressure;
        p0              uniform 1e5;
    }

See also: Foam::dynamicPressureFvPatchScalarField Foam::fixedValueFvPatchField

Source files

Definition at line 261 of file totalPressureFvPatchScalarField.H.

Constructor & Destructor Documentation

◆ totalPressureFvPatchScalarField() [1/5]

totalPressureFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF
	)

Construct from patch and internal field.

Definition at line 35 of file totalPressureFvPatchScalarField.C.

Referenced by totalPressureFvPatchScalarField::clone(), and totalPressureFvPatchScalarField::totalPressureFvPatchScalarField().

Here is the caller graph for this function:

◆ totalPressureFvPatchScalarField() [2/5]

totalPressureFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const dictionary &	dict
	)

Construct from patch, internal field and dictionary.

Definition at line 47 of file totalPressureFvPatchScalarField.C.

References totalPressureFvPatchScalarField::totalPressureFvPatchScalarField().

Here is the call graph for this function:

◆ totalPressureFvPatchScalarField() [3/5]

totalPressureFvPatchScalarField	(	const totalPressureFvPatchScalarField &	ptf,
		const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const fvPatchFieldMapper &	mapper
	)

Construct by mapping given totalPressureFvPatchScalarField.

onto a new patch

Definition at line 60 of file totalPressureFvPatchScalarField.C.

References totalPressureFvPatchScalarField::totalPressureFvPatchScalarField().

Here is the call graph for this function:

◆ totalPressureFvPatchScalarField() [4/5]

totalPressureFvPatchScalarField ( const totalPressureFvPatchScalarField & tppsf )

Copy constructor.

Definition at line 74 of file totalPressureFvPatchScalarField.C.

References totalPressureFvPatchScalarField::totalPressureFvPatchScalarField().

Here is the call graph for this function:

◆ totalPressureFvPatchScalarField() [5/5]

totalPressureFvPatchScalarField	(	const totalPressureFvPatchScalarField &	tppsf,
		const DimensionedField< scalar, volMesh > &	iF
	)

Copy constructor setting internal field reference.

Definition at line 85 of file totalPressureFvPatchScalarField.C.

References totalPressureFvPatchScalarField::updateCoeffs().

Here is the call graph for this function:

Member Function Documentation

◆ TypeName()

TypeName ( "totalPressure" )

Runtime type information.

◆ clone() [1/2]

virtual tmp<fvPatchScalarField> clone ( ) const

inlinevirtual

Construct and return a clone.

Reimplemented in fanPressureFvPatchScalarField, and rotatingTotalPressureFvPatchScalarField.

Definition at line 316 of file totalPressureFvPatchScalarField.H.

References totalPressureFvPatchScalarField::totalPressureFvPatchScalarField().

Here is the call graph for this function:

◆ clone() [2/2]

virtual tmp<fvPatchScalarField> clone ( const DimensionedField< scalar, volMesh > & iF ) const

inlinevirtual

Construct and return a clone setting internal field reference.

Reimplemented in fanPressureFvPatchScalarField, and rotatingTotalPressureFvPatchScalarField.

Definition at line 333 of file totalPressureFvPatchScalarField.H.

References totalPressureFvPatchScalarField::totalPressureFvPatchScalarField(), totalPressureFvPatchScalarField::updateCoeffs(), and totalPressureFvPatchScalarField::write().

Here is the call graph for this function:

◆ updateCoeffs() [1/2]

void updateCoeffs	(	const scalarField &	p0p,
		const vectorField &	Up
	)

Update the coefficients associated with the patch field.

using the given patch total pressure and velocity fields

Definition at line 99 of file totalPressureFvPatchScalarField.C.

References Foam::magSqr(), and Foam::pos0().

Here is the call graph for this function:

◆ updateCoeffs() [2/2]

void updateCoeffs ( )

virtual

Update the coefficients associated with the patch field.

Reimplemented in fanPressureFvPatchScalarField, and rotatingTotalPressureFvPatchScalarField.

Definition at line 115 of file totalPressureFvPatchScalarField.C.

References dynamicPressureFvPatchScalarField::p0_, and totalPressureFvPatchScalarField::UName_.

Referenced by totalPressureFvPatchScalarField::clone(), totalPressureFvPatchScalarField::totalPressureFvPatchScalarField(), rotatingTotalPressureFvPatchScalarField::updateCoeffs(), and fanPressureFvPatchScalarField::updateCoeffs().

Here is the caller graph for this function:

◆ write()

void write ( Ostream & os ) const

virtual

Write.

Reimplemented from dynamicPressureFvPatchScalarField.

Reimplemented in fanPressureFvPatchScalarField, and rotatingTotalPressureFvPatchScalarField.

Definition at line 124 of file totalPressureFvPatchScalarField.C.

References Foam::makePatchTypeField(), totalPressureFvPatchScalarField::phiName_, totalPressureFvPatchScalarField::UName_, and dynamicPressureFvPatchScalarField::write().

Referenced by totalPressureFvPatchScalarField::clone(), rotatingTotalPressureFvPatchScalarField::write(), and fanPressureFvPatchScalarField::write().

Here is the call graph for this function:

Here is the caller graph for this function:

Member Data Documentation

◆ UName_

const word UName_

protected

Name of the velocity field.

Definition at line 270 of file totalPressureFvPatchScalarField.H.

Referenced by rotatingTotalPressureFvPatchScalarField::updateCoeffs(), totalPressureFvPatchScalarField::updateCoeffs(), and totalPressureFvPatchScalarField::write().

◆ phiName_

const word phiName_

protected

Name of the flux field.

Definition at line 273 of file totalPressureFvPatchScalarField.H.

Referenced by totalPressureFvPatchScalarField::write().

The documentation for this class was generated from the following files:

src/finiteVolume/fields/fvPatchFields/derived/totalPressure/totalPressureFvPatchScalarField.H
src/finiteVolume/fields/fvPatchFields/derived/totalPressure/totalPressureFvPatchScalarField.C

Public Member Functions

Protected Attributes

Detailed Description

Constructor & Destructor Documentation

◆ totalPressureFvPatchScalarField() [1/5]

◆ totalPressureFvPatchScalarField() [2/5]

◆ totalPressureFvPatchScalarField() [3/5]

◆ totalPressureFvPatchScalarField() [4/5]

◆ totalPressureFvPatchScalarField() [5/5]

Member Function Documentation

◆ TypeName()

◆ clone() [1/2]

◆ clone() [2/2]

◆ updateCoeffs() [1/2]

◆ updateCoeffs() [2/2]

◆ write()

Member Data Documentation

◆ UName_

◆ phiName_