Mixed boundary condition for temperature, to be used for heat-transfer on back-to-back baffles. Optional thin thermal layer resistances can be specified through thicknessLayers and kappaLayers entries. More...

Inheritance diagram for turbulentTemperatureCoupledBaffleMixedFvPatchScalarField:

[legend]

Collaboration diagram for turbulentTemperatureCoupledBaffleMixedFvPatchScalarField:

[legend]

Public Member Functions
	TypeName ("compressible::turbulentTemperatureCoupledBaffleMixed")
	Runtime type information. More...

	turbulentTemperatureCoupledBaffleMixedFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &)
	Construct from patch and internal field. More...

	turbulentTemperatureCoupledBaffleMixedFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)
	Construct from patch, internal field and dictionary. More...

	turbulentTemperatureCoupledBaffleMixedFvPatchScalarField (const turbulentTemperatureCoupledBaffleMixedFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)
	Construct by mapping given. More...

	turbulentTemperatureCoupledBaffleMixedFvPatchScalarField (const turbulentTemperatureCoupledBaffleMixedFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)
	Construct as copy setting internal field reference. More...

virtual tmp< fvPatchScalarField >	clone (const DimensionedField< scalar, volMesh > &iF) const
	Construct and return a clone setting internal field reference. More...

virtual void	updateCoeffs ()
	Update the coefficients associated with the patch field. More...

virtual void	write (Ostream &) const
	Write. More...

Public Member Functions inherited from temperatureCoupledBase
	temperatureCoupledBase (const fvPatch &patch)
	Construct from patch. More...

	temperatureCoupledBase (const fvPatch &patch, const dictionary &dict)
	Construct from patch and dictionary. More...

	temperatureCoupledBase (const fvPatch &patch, const temperatureCoupledBase &base)
	Construct from patch and temperatureCoupledBase. More...

tmp< scalarField >	kappa (const fvPatchScalarField &Tp) const
	Given patch temperature calculate corresponding K field. More...

void	write (Ostream &) const
	Write. More...

Detailed Description

Mixed boundary condition for temperature, to be used for heat-transfer on back-to-back baffles. Optional thin thermal layer resistances can be specified through thicknessLayers and kappaLayers entries.

Specifies gradient and temperature such that the equations are the same on both sides:

refGradient = qs_/kappa
refValue = neighbour value
mixFraction = nbrKDelta/(nbrKDelta + myKDelta())

where KDelta is heat-transfer coefficient K*deltaCoeffs and qs is the optional source heat flux.

The thermal conductivity kappa can either be retrieved from various possible sources, as detailed in the class temperatureCoupledBase.

Usage

Property	Description	Required	Default value
`Tnbr`	name of the field	no	T
`thicknessLayers`	list of thicknesses per layer [m]	no
`kappaLayers`	list of thermal conductivities per layer [W/m/K]	no
`qs`	Optional source heat flux [W/m^2]	no	0
`Qs`	Optional heat source [W]	no	0

Example of the boundary condition specification:

    <patchName>
    {
        type            compressible::turbulentTemperatureCoupledBaffleMixed;
        Tnbr            T;
        thicknessLayers (0.1 0.2 0.3 0.4);
        kappaLayers     (1 2 3 4);
        qs              uniform 100;    // Optional source heat flux [W/m^2]
        value           uniform 300;
    }

Needs to be on underlying mapped(Wall)FvPatch.

Note that in order to provide an optional heat source either qs or Qs should be specified, not both.

See also: Foam::temperatureCoupledBase

Source files

Definition at line 127 of file turbulentTemperatureCoupledBaffleMixedFvPatchScalarField.H.

Constructor & Destructor Documentation

◆ turbulentTemperatureCoupledBaffleMixedFvPatchScalarField() [1/4]

turbulentTemperatureCoupledBaffleMixedFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF
	)

Construct from patch and internal field.

Definition at line 43 of file turbulentTemperatureCoupledBaffleMixedFvPatchScalarField.C.

Referenced by turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::clone(), and turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::turbulentTemperatureCoupledBaffleMixedFvPatchScalarField().

Here is the caller graph for this function:

◆ turbulentTemperatureCoupledBaffleMixedFvPatchScalarField() [2/4]

turbulentTemperatureCoupledBaffleMixedFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const dictionary &	dict
	)

Construct from patch, internal field and dictionary.

Definition at line 64 of file turbulentTemperatureCoupledBaffleMixedFvPatchScalarField.C.

References Foam::exit(), Foam::FatalError, FatalErrorInFunction, Foam::FatalIOError, FatalIOErrorInFunction, forAll, dictionary::found(), Foam::gSum(), dictionary::lookup(), fvPatch::name(), fvPatchField< Type >::operator=(), fvPatch::size(), and turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::turbulentTemperatureCoupledBaffleMixedFvPatchScalarField().

Here is the call graph for this function:

◆ turbulentTemperatureCoupledBaffleMixedFvPatchScalarField() [3/4]

turbulentTemperatureCoupledBaffleMixedFvPatchScalarField	(	const turbulentTemperatureCoupledBaffleMixedFvPatchScalarField &	ptf,
		const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const fvPatchFieldMapper &	mapper
	)

Construct by mapping given.

turbulentTemperatureCoupledBaffleMixedFvPatchScalarField onto a new patch

Definition at line 145 of file turbulentTemperatureCoupledBaffleMixedFvPatchScalarField.C.

References turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::turbulentTemperatureCoupledBaffleMixedFvPatchScalarField().

Here is the call graph for this function:

◆ turbulentTemperatureCoupledBaffleMixedFvPatchScalarField() [4/4]

turbulentTemperatureCoupledBaffleMixedFvPatchScalarField	(	const turbulentTemperatureCoupledBaffleMixedFvPatchScalarField &	ptf,
		const DimensionedField< scalar, volMesh > &	iF
	)

Construct as copy setting internal field reference.

Definition at line 164 of file turbulentTemperatureCoupledBaffleMixedFvPatchScalarField.C.

Member Function Documentation

◆ TypeName()

TypeName ( "compressible::turbulentTemperatureCoupledBaffleMixed" )

Runtime type information.

◆ clone()

virtual tmp<fvPatchScalarField> clone ( const DimensionedField< scalar, volMesh > & iF ) const

inlinevirtual

Construct and return a clone setting internal field reference.

Definition at line 193 of file turbulentTemperatureCoupledBaffleMixedFvPatchScalarField.H.

References turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::turbulentTemperatureCoupledBaffleMixedFvPatchScalarField(), turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::updateCoeffs(), and turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::write().

Here is the call graph for this function:

◆ updateCoeffs()

void updateCoeffs ( )

virtual

Update the coefficients associated with the patch field.

Definition at line 181 of file turbulentTemperatureCoupledBaffleMixedFvPatchScalarField.C.

References boundary(), fvPatch::deltaCoeffs(), mappedPatchBase::distribute(), Foam::endl(), Foam::exit(), Foam::FatalError, FatalErrorInFunction, Foam::gAverage(), Foam::gMax(), Foam::gMin(), Foam::gSum(), patchIdentifier::index(), Foam::Info, temperatureCoupledBase::kappa(), fvPatch::lookupPatchField(), UPstream::msgType(), fvPatch::name(), tmp< T >::ref(), mappedPatchBase::sampleMesh(), mappedPatchBase::samplePolyPatch(), Foam::fvc::snGrad(), and turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::write().

Referenced by turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::clone().

Here is the call graph for this function:

Here is the caller graph for this function:

◆ write()

void write ( Ostream & os ) const

virtual

Write.

Definition at line 286 of file turbulentTemperatureCoupledBaffleMixedFvPatchScalarField.C.

References Foam::compressible::makePatchTypeField(), Foam::vtkWriteOps::write(), temperatureCoupledBase::write(), and Foam::writeEntry().

Referenced by turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::clone(), and turbulentTemperatureCoupledBaffleMixedFvPatchScalarField::updateCoeffs().

Here is the call graph for this function:

Here is the caller graph for this function:

The documentation for this class was generated from the following files:

src/ThermophysicalTransportModels/derivedFvPatchFields/turbulentTemperatureCoupledBaffleMixed/turbulentTemperatureCoupledBaffleMixedFvPatchScalarField.H
src/ThermophysicalTransportModels/derivedFvPatchFields/turbulentTemperatureCoupledBaffleMixed/turbulentTemperatureCoupledBaffleMixedFvPatchScalarField.C

Public Member Functions

Detailed Description

Constructor & Destructor Documentation

◆ turbulentTemperatureCoupledBaffleMixedFvPatchScalarField() [1/4]

◆ turbulentTemperatureCoupledBaffleMixedFvPatchScalarField() [2/4]

◆ turbulentTemperatureCoupledBaffleMixedFvPatchScalarField() [3/4]

◆ turbulentTemperatureCoupledBaffleMixedFvPatchScalarField() [4/4]

Member Function Documentation

◆ TypeName()

◆ clone()

◆ updateCoeffs()

◆ write()