turbulentMixingLengthDissipationRateFvScalarFieldSource.H

Go to the documentation of this file.

/*---------------------------------------------------------------------------*\
  =========                 |
  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
   \\    /   O peration     | Website:  https://openfoam.org
    \\  /    A nd           | Copyright (C) 2023 OpenFOAM Foundation
     \\/     M anipulation  |
-------------------------------------------------------------------------------
License
    This file is part of OpenFOAM.
 
    OpenFOAM is free software: you can redistribute it and/or modify it
    under the terms of the GNU General Public License as published by
    the Free Software Foundation, either version 3 of the License, or
    (at your option) any later version.
 
    OpenFOAM is distributed in the hope that it will be useful, but WITHOUT
    ANY WARRANTY; without even the implied warranty of MERCHANTABILITY or
    FITNESS FOR A PARTICULAR PURPOSE.  See the GNU General Public License
    for more details.
 
    You should have received a copy of the GNU General Public License
    along with OpenFOAM.  If not, see <http://www.gnu.org/licenses/>.
 
Class
    Foam::turbulentMixingLengthDissipationRateFvScalarFieldSource
 
Description
    This source condition provides a turbulence dissipation, \f$\epsilon\f$
    (epsilon), based on a specified mixing length. The source values are
    calculated using:
 
        \f[
            \epsilon = \frac{C_{\mu}^{0.75} k^{1.5}}{L}
        \f]
 
    where
 
    \vartable
        \epsilon | epsilon values
        C_{\mu}  | Model coefficient, set to 0.09
        k        | turbulence kinetic energy
        L        | length scale
    \endvartable
 
    In the case of a sink, the current cell values are used instead.
 
Usage
    \table
        Property     | Description             | Required    | Default value
        mixingLength | Length scale [m]        | yes         |
        k            | turbulence kinetic energy field name | no | k
    \endtable
 
    Example of the source condition specification:
    \verbatim
    <patchName>
    {
        type            turbulentMixingLengthDissipationRate;
        mixingLength    0.005;
    }
    \endverbatim
 
SourceFiles
    turbulentMixingLengthDissipationRateFvScalarFieldSource.C
 
\*---------------------------------------------------------------------------*/
 
#ifndef turbulentMixingLengthDissipationRateFvScalarFieldSource_H
#define turbulentMixingLengthDissipationRateFvScalarFieldSource_H
 
#include "fvFieldSources.H"
 
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
 
namespace Foam
{
 
/*---------------------------------------------------------------------------*\
   Class turbulentMixingLengthDissipationRateFvScalarFieldSource Declaration
\*---------------------------------------------------------------------------*/
 
class turbulentMixingLengthDissipationRateFvScalarFieldSource
:
    public fvScalarFieldSource
{
private:
 
    // Private Data
 
        //- Turbulent length scale
        scalar mixingLength_;
 
        //- Name of the turbulent kinetic energy field
        word kName_;
 
 
public:
 
    //- Runtime type information
    TypeName("turbulentMixingLengthDissipationRate");
 
 
    // Constructors
 
        //- Construct from internal field and dictionary
        turbulentMixingLengthDissipationRateFvScalarFieldSource
        (
            const DimensionedField<scalar, volMesh>&,
            const dictionary& dict
        );
 
        //- Copy constructor setting internal field reference
        turbulentMixingLengthDissipationRateFvScalarFieldSource
        (
            const turbulentMixingLengthDissipationRateFvScalarFieldSource&,
            const DimensionedField<scalar, volMesh>&
        );
 
        //- Construct and return a clone setting internal field reference
        virtual autoPtr<fvScalarFieldSource> clone
        (
            const DimensionedField<scalar, volMesh>& iF
        ) const
        {
            return autoPtr<fvScalarFieldSource>
            (
                new turbulentMixingLengthDissipationRateFvScalarFieldSource
                (
                    *this,
                    iF
                )
            );
        }
 
 
    //- Destructor
    virtual ~turbulentMixingLengthDissipationRateFvScalarFieldSource();
 
 
    // Member Functions
 
        //- Return the source value
        virtual tmp<scalarField> sourceValue(const fvSource&) const;
 
        //- Return the internal coefficient
        virtual tmp<scalarField> internalCoeff(const fvSource&) const;
 
        //- Write
        virtual void write(Ostream&) const;
};
 
 
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
 
} // End namespace Foam
 
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
 
#endif
 
// ************************************************************************* //