Mixed boundary condition for temperature, to be used for heat-transfer with another region in a CHT case. Optional thin wall material layer resistances can be specified through thicknessLayers and kappaLayers entries. More...

Inheritance diagram for coupledTemperatureFvPatchScalarField:

[legend]

Collaboration diagram for coupledTemperatureFvPatchScalarField:

[legend]

Public Member Functions
	TypeName ("coupledTemperature")
	Runtime type information. More...

	coupledTemperatureFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)
	Construct from patch, internal field and dictionary. More...

	coupledTemperatureFvPatchScalarField (const coupledTemperatureFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)
	Construct by mapping given. More...

	coupledTemperatureFvPatchScalarField (const coupledTemperatureFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)
	Construct as copy setting internal field reference. More...

virtual tmp< fvPatchScalarField >	clone (const DimensionedField< scalar, volMesh > &iF) const
	Construct and return a clone setting internal field reference. More...

virtual void	updateCoeffs ()
	Update the coefficients associated with the patch field. More...

virtual void	write (Ostream &) const
	Write. More...

Protected Member Functions
virtual void	getThis (tmp< scalarField > &kappa, tmp< scalarField > &sumKappaTByDelta, tmp< scalarField > &sumKappaByDelta, scalarField &qTot, tmp< scalarField > &qByKappa) const
	Get the patch kappa, kappa*Tc/delta and kappa/delta and also the. More...

virtual void	getNbr (tmp< scalarField > &sumKappaTByDeltaNbr, tmp< scalarField > &sumKappaByDeltaNbr, tmp< scalarField > &qNbr) const
	Get the neighbour patch kappa*Tc/delta and kappa/delta. More...

virtual void	getNbr (tmp< scalarField > &TwNbr, tmp< scalarField > &qNbr) const
	Get the neighbour patch wall temperature and heat-flux. More...

void	add (tmp< scalarField > &result, const tmp< scalarField > &field) const
	Add field to result which may have not been previously set. More...

Detailed Description

Mixed boundary condition for temperature, to be used for heat-transfer with another region in a CHT case. Optional thin wall material layer resistances can be specified through thicknessLayers and kappaLayers entries.

Specifies gradient and temperature such that the equations are the same on both sides:

refGradient = qs_/kappa
refValue = neighbour value
valueFraction = kappaByDeltaNbr/(kappaByDeltaNbr + kappaByDelta)

where kappaByDelta is heat-transfer coefficient kappa*deltaCoeffs and qs is the optional source heat flux.

Usage

Property	Description	Required	Default value
`Tnbr`	name of the field	no	T
`thicknessLayers`	list of thicknesses per layer [m]	no
`kappaLayers`	list of thermal conductivities per layer [W/m/K]	no
`qs`	Optional source heat flux [W/m^2]	no	0
`Qs`	Optional heat source [W]	no	0
`qrNbr`	name of the radiative flux in the nbr region	no	none
`qr`	name of the radiative flux in this region	no	none

Example of the boundary condition specification:

    <patchName>
    {
        type            coupledTemperature;
        thicknessLayers (0.1 0.2 0.3 0.4); // Optional wall layer thicknesses
        kappaLayers     (1 2 3 4); // Optional wall layer conductivities
        qs              uniform 100;    // Optional source heat flux [W/m^2]
        value           uniform 300;
    }

Needs to be on underlying mapped(Wall)FvPatch.

The patch thermal conductivity kappa is obtained from the region thermophysicalTransportModel so that this boundary condition can be applied directly to either fluid or solid regions.

Note that in order to provide an optional heat source either qs or Qs should be specified, not both.

Source files

Definition at line 134 of file coupledTemperatureFvPatchScalarField.H.

Constructor & Destructor Documentation

◆ coupledTemperatureFvPatchScalarField() [1/3]

coupledTemperatureFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const dictionary &	dict
	)

Construct from patch, internal field and dictionary.

Definition at line 130 of file coupledTemperatureFvPatchScalarField.C.

References dict, mappedPatchBase::from::differentPatch, Foam::exit(), Foam::FatalIOError, FatalIOErrorInFunction, forAll, Foam::gSum(), fvPatchField< Type >::operator=(), p, List< T >::size(), and mappedPatchBase::validateMapForField().

Here is the call graph for this function:

◆ coupledTemperatureFvPatchScalarField() [2/3]

coupledTemperatureFvPatchScalarField	(	const coupledTemperatureFvPatchScalarField &	psf,
		const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const fvPatchFieldMapper &	mapper
	)

Construct by mapping given.

coupledTemperatureFvPatchScalarField onto a new patch

Definition at line 208 of file coupledTemperatureFvPatchScalarField.C.

◆ coupledTemperatureFvPatchScalarField() [3/3]

coupledTemperatureFvPatchScalarField	(	const coupledTemperatureFvPatchScalarField &	psf,
		const DimensionedField< scalar, volMesh > &	iF
	)

Construct as copy setting internal field reference.

Definition at line 234 of file coupledTemperatureFvPatchScalarField.C.

Member Function Documentation

◆ getThis()

void getThis	(	tmp< scalarField > &	kappa,
		tmp< scalarField > &	sumKappaTByDelta,
		tmp< scalarField > &	sumKappaByDelta,
		scalarField &	qTot,
		tmp< scalarField > &	qByKappa
	)		const

protectedvirtual

Get the patch kappa, kappa*Tc/delta and kappa/delta and also the.

heat-flux obtained from the sum heat-flux provided

Reimplemented in coupledMultiphaseTemperatureFvPatchScalarField.

Definition at line 35 of file coupledTemperatureFvPatchScalarField.C.

References Foam::constant::electromagnetic::kappa, thermophysicalTransportModel::kappaEff(), thermophysicalTransportModel::qCorr(), and tmp< T >::valid().

Here is the call graph for this function:

◆ getNbr() [1/2]

void getNbr	(	tmp< scalarField > &	sumKappaTByDeltaNbr,
		tmp< scalarField > &	sumKappaByDeltaNbr,
		tmp< scalarField > &	qNbr
	)		const

protectedvirtual

Get the neighbour patch kappa*Tc/delta and kappa/delta.

and the heat-flux correction

Reimplemented in coupledMultiphaseTemperatureFvPatchScalarField.

Definition at line 63 of file coupledTemperatureFvPatchScalarField.C.

References thermophysicalTransportModel::kappaEff(), and thermophysicalTransportModel::qCorr().

Referenced by coupledTemperatureFvPatchScalarField::updateCoeffs().

Here is the call graph for this function:

Here is the caller graph for this function:

◆ getNbr() [2/2]

void getNbr	(	tmp< scalarField > &	TwNbr,
		tmp< scalarField > &	qNbr
	)		const

protectedvirtual

Get the neighbour patch wall temperature and heat-flux.

when wall thermal resistance is specified

Reimplemented in coupledMultiphaseTemperatureFvPatchScalarField.

Definition at line 82 of file coupledTemperatureFvPatchScalarField.C.

References thermophysicalTransportModel::qCorr().

Here is the call graph for this function:

◆ add()

void add	(	tmp< scalarField > &	result,
		const tmp< scalarField > &	field
	)		const

protected

Add field to result which may have not been previously set.

Definition at line 104 of file coupledTemperatureFvPatchScalarField.C.

References tmp< T >::isTmp(), tmp< T >::ref(), and tmp< T >::valid().

Here is the call graph for this function:

◆ TypeName()

TypeName ( "coupledTemperature" )

Runtime type information.

◆ clone()

virtual tmp<fvPatchScalarField> clone ( const DimensionedField< scalar, volMesh > & iF ) const

inlinevirtual

Construct and return a clone setting internal field reference.

Reimplemented in coupledMultiphaseTemperatureFvPatchScalarField.

Definition at line 238 of file coupledTemperatureFvPatchScalarField.H.

◆ updateCoeffs()

void updateCoeffs ( )

virtual

Update the coefficients associated with the patch field.

Definition at line 255 of file coupledTemperatureFvPatchScalarField.C.

References Foam::add(), Foam::endl(), Foam::exit(), Foam::FatalError, FatalErrorInFunction, mappedPatchBase::fromNeighbour(), Foam::gAverage(), mappedPatchBase::getMap(), coupledTemperatureFvPatchScalarField::getNbr(), Foam::gMax(), Foam::gMin(), Foam::gSum(), patchIdentifier::index(), Foam::Info, Foam::constant::electromagnetic::kappa, fvPatch::lookupPatchField(), UPstream::msgType(), fvPatch::name(), IOobject::name(), IOstream::name(), mappedPatchBase::nbrMesh(), mappedPatchBase::nbrPolyPatch(), Foam::fvc::snGrad(), and tmp< T >::valid().

Here is the call graph for this function:

◆ write()

void write ( Ostream & os ) const

virtual

Write.

Definition at line 385 of file coupledTemperatureFvPatchScalarField.C.

References Foam::vtkWriteOps::write(), and Foam::writeEntry().

Here is the call graph for this function:

The documentation for this class was generated from the following files:

src/ThermophysicalTransportModels/coupledThermophysicalTransportModels/coupledTemperature/coupledTemperatureFvPatchScalarField.H
src/ThermophysicalTransportModels/coupledThermophysicalTransportModels/coupledTemperature/coupledTemperatureFvPatchScalarField.C

Public Member Functions

Protected Member Functions

Detailed Description

Constructor & Destructor Documentation

◆ coupledTemperatureFvPatchScalarField() [1/3]

◆ coupledTemperatureFvPatchScalarField() [2/3]

◆ coupledTemperatureFvPatchScalarField() [3/3]

Member Function Documentation

◆ getThis()

◆ getNbr() [1/2]

◆ getNbr() [2/2]

◆ add()

◆ TypeName()

◆ clone()

◆ updateCoeffs()

◆ write()